Note

Go to the end to download the full example code.

MeshConvergence#

Verification of energy convergence for a bending beam for all available elements.

  • MeshConvergence
  • MeshConvergence
  • MeshConvergence
  • MeshConvergence
  • $\sigma_{vm}$
Elem: TRI3, nby:  1, Wdef = 85.307, error = 7.71e-01
Elem: TRI3, nby:  2, Wdef = 199.836, error = 4.63e-01
Elem: TRI3, nby:  3, Wdef = 268.382, error = 2.79e-01
Elem: TRI3, nby:  4, Wdef = 305.294, error = 1.79e-01
Elem: TRI3, nby:  5, Wdef = 326.756, error = 1.22e-01
Elem: TRI3, nby:  6, Wdef = 339.109, error = 8.85e-02
Elem: TRI3, nby:  7, Wdef = 347.06, error = 6.71e-02
Elem: TRI3, nby:  8, Wdef = 352.445, error = 5.26e-02
Elem: TRI3, nby:  9, Wdef = 356.373, error = 4.21e-02
Elem: TRI6, nby:  1, Wdef = 369.006, error = 8.10e-03
Elem: TRI6, nby:  2, Wdef = 370.965, error = 2.84e-03
Elem: TRI6, nby:  3, Wdef = 371.253, error = 2.06e-03
Elem: TRI6, nby:  4, Wdef = 371.354, error = 1.79e-03
Elem: TRI6, nby:  5, Wdef = 371.405, error = 1.65e-03
Elem: TRI6, nby:  6, Wdef = 371.433, error = 1.58e-03
Elem: TRI6, nby:  7, Wdef = 371.451, error = 1.53e-03
Elem: TRI6, nby:  8, Wdef = 371.463, error = 1.50e-03
Elem: TRI6, nby:  9, Wdef = 371.472, error = 1.47e-03
Elem: TRI10, nby:  1, Wdef = 371.008, error = 2.72e-03
Elem: TRI10, nby:  2, Wdef = 371.36, error = 1.78e-03
Elem: TRI10, nby:  3, Wdef = 371.433, error = 1.58e-03
Elem: TRI10, nby:  4, Wdef = 371.463, error = 1.50e-03
Elem: TRI10, nby:  5, Wdef = 371.479, error = 1.45e-03
Elem: TRI10, nby:  6, Wdef = 371.489, error = 1.43e-03
Elem: TRI10, nby:  7, Wdef = 371.495, error = 1.41e-03
Elem: TRI10, nby:  8, Wdef = 371.499, error = 1.40e-03
Elem: TRI10, nby:  9, Wdef = 371.503, error = 1.39e-03
Elem: TRI15, nby:  1, Wdef = 371.309, error = 1.91e-03
Elem: TRI15, nby:  2, Wdef = 371.445, error = 1.55e-03
Elem: TRI15, nby:  3, Wdef = 371.478, error = 1.46e-03
Elem: TRI15, nby:  4, Wdef = 371.493, error = 1.42e-03
Elem: TRI15, nby:  5, Wdef = 371.501, error = 1.40e-03
Elem: TRI15, nby:  6, Wdef = 371.505, error = 1.39e-03
Elem: TRI15, nby:  7, Wdef = 371.508, error = 1.38e-03
Elem: TRI15, nby:  8, Wdef = 371.511, error = 1.37e-03
Elem: TRI15, nby:  9, Wdef = 371.512, error = 1.37e-03
Elem: QUAD4, nby:  1, Wdef = 249.865, error = 3.28e-01
Elem: QUAD4, nby:  2, Wdef = 330.381, error = 1.12e-01
Elem: QUAD4, nby:  3, Wdef = 351.849, error = 5.42e-02
Elem: QUAD4, nby:  4, Wdef = 360.11, error = 3.20e-02
Elem: QUAD4, nby:  5, Wdef = 364.354, error = 2.06e-02
Elem: QUAD4, nby:  6, Wdef = 366.455, error = 1.50e-02
Elem: QUAD4, nby:  7, Wdef = 367.75, error = 1.15e-02
Elem: QUAD4, nby:  8, Wdef = 368.603, error = 9.19e-03
Elem: QUAD4, nby:  9, Wdef = 369.241, error = 7.47e-03
Elem: QUAD8, nby:  1, Wdef = 369.262, error = 7.42e-03
Elem: QUAD8, nby:  2, Wdef = 371.115, error = 2.43e-03
Elem: QUAD8, nby:  3, Wdef = 371.315, error = 1.90e-03
Elem: QUAD8, nby:  4, Wdef = 371.386, error = 1.70e-03
Elem: QUAD8, nby:  5, Wdef = 371.424, error = 1.60e-03
Elem: QUAD8, nby:  6, Wdef = 371.445, error = 1.55e-03
Elem: QUAD8, nby:  7, Wdef = 371.46, error = 1.51e-03
Elem: QUAD8, nby:  8, Wdef = 371.47, error = 1.48e-03
Elem: QUAD8, nby:  9, Wdef = 371.478, error = 1.46e-03
Elem: QUAD9, nby:  1, Wdef = 370.315, error = 4.58e-03
Elem: QUAD9, nby:  2, Wdef = 371.231, error = 2.12e-03
Elem: QUAD9, nby:  3, Wdef = 371.375, error = 1.74e-03
Elem: QUAD9, nby:  4, Wdef = 371.428, error = 1.59e-03
Elem: QUAD9, nby:  5, Wdef = 371.456, error = 1.52e-03
Elem: QUAD9, nby:  6, Wdef = 371.471, error = 1.48e-03
Elem: QUAD9, nby:  7, Wdef = 371.481, error = 1.45e-03
Elem: QUAD9, nby:  8, Wdef = 371.488, error = 1.43e-03
Elem: QUAD9, nby:  9, Wdef = 371.494, error = 1.42e-03

WSA = 372.0206 mJ

Mesh: 1.143 s
Boundary Conditions: 1.036 ms
Matrix: 1.644 s
Solver: 1.004 s
Resolutions: 2.173 s
PostProcessing: 278.500 ms
Display: 1.166 s


 13 import matplotlib.pyplot as plt
 14 import numpy as np
 15
 16 from EasyFEA import Display, Folder, Models, Tic, ElemType, Simulations, Paraview
 17 from EasyFEA.Geoms import Domain, Point
 18
 19 if __name__ == "__main__":
 20     Display.Clear()
 21
 22     # ----------------------------------------------
 23     # Configuration
 24     # ----------------------------------------------
 25     dim = 2  # Define the dimension of the problem (2D or 3D)
 26
 27     # outputs
 28     folder = Folder.Results_Dir() + f"{dim}D"
 29     plotResult = True
 30     makeParaview = False
 31
 32     # geom
 33     L = 120  # mm
 34     h = 13  # Height
 35     b = 13  # Width
 36
 37     # model
 38     E = 210000  # MPa (Young's modulus)
 39     v = 0.25  # Poisson's ratio
 40     material = Models.Elastic.Isotropic(dim, thickness=b, E=E, v=v, planeStress=True)
 41
 42     # load
 43     P = 800  # N
 44
 45     # expected energy
 46     WdefRef = 2 * P**2 * L / E / h / b * (L**2 / h / b + (1 + v) * 3 / 5)
 47
 48     # ----------------------------------------------
 49     # Mesh
 50     # ----------------------------------------------
 51     isOrganised = True
 52
 53     # List of mesh sizes (number of elements) to investigate convergence
 54     if dim == 2:
 55         list_N = np.arange(1, 10, 1)
 56     else:
 57         list_N = np.arange(1, 8, 2)
 58
 59     # Lists to store data for plotting
 60     times_elem_N = []  # times for element type and N size
 61     wDef_elem_N = []  # energy
 62     dofs_elem_N = []  # dofs
 63     zz1_elem_N = []  # zz1
 64
 65     # ----------------------------------------------
 66     # Simulations
 67     # ----------------------------------------------
 68
 69     # Loop over each element type for both 2D and 3D simulations
 70     elemTypes = ElemType.Get_2D()[:] if dim == 2 else ElemType.Get_3D()
 71
 72     # elemTypes = [elem.name for elem in elemTypes.copy()]
 73
 74     for e, elemType in enumerate(elemTypes):
 75         times_N = []
 76         wDef_N = []
 77         dofs_N = []
 78         zz1_N = []
 79
 80         # Loop over each mesh size (number of elements)
 81         for N in list_N:
 82             meshSize = b / N
 83
 84             # Define the domain for the mesh
 85             domain = Domain(Point(), Point(x=L, y=h), meshSize)
 86
 87             # Generate the mesh using Gmsh
 88             if dim == 2:
 89                 mesh = domain.Mesh_2D([], elemType, isOrganised=isOrganised)
 90                 volume = mesh.area * material.thickness
 91             else:
 92                 mesh = domain.Mesh_Extrude(
 93                     [],
 94                     elemType=elemType,
 95                     extrude=[0, 0, b],
 96                     layers=[4],
 97                     isOrganised=isOrganised,
 98                 )
 99                 volume = mesh.volume
100             # Ensure that the volume matches the expected value (L * h * b)
101             assert np.abs(volume - (L * h * b)) / volume <= 1e-10
102
103             # Define nodes on the left boundary (x=0) and right boundary (x=L)
104             nodes_x0 = mesh.Nodes_Conditions(lambda x, y, z: x == 0)
105             nodes_xL = mesh.Nodes_Conditions(lambda x, y, z: x == L)
106
107             # Create or update the simulation object with the current mesh
108             if e == 0 and N == list_N[0]:
109                 simu = Simulations.Elastic(mesh, material)
110             else:
111                 simu.Bc_Init()
112                 simu.mesh = mesh
113
114             # Set displacement boundary conditions
115             simu.add_dirichlet(nodes_x0, [0] * dim, simu.Get_unknowns())
116             # Set surface load on the right boundary (y-direction)
117             simu.add_surfLoad(nodes_xL, [-P / h / b], ["y"])
118
119             tic = Tic()
120
121             # Solve the simulation
122             simu.Solve()
123             simu.Save_Iter()
124
125             time = tic.Tac("Resolutions", "Total time", False)
126
127             # Get the computed deformation energy
128             Wdef = simu.Result("Wdef")
129
130             # Store the results for the current mesh size
131             times_N.append(time)
132             wDef_N.append(Wdef)
133             dofs_N.append(mesh.Nn * dim)
134             zz1_N.append(simu.Result("ZZ1"))
135
136             if elemType != mesh.elemType:
137                 print("Error in mesh generation")
138
139             print(
140                 f"Elem: {mesh.elemType}, nby: {N:2}, Wdef = {np.round(Wdef, 3)}, "
141                 f"error = {np.abs(WdefRef - Wdef) / WdefRef:.2e}"
142             )
143
144         # Store the results for the current element type
145         times_elem_N.append(times_N)
146         wDef_elem_N.append(wDef_N)
147         dofs_elem_N.append(dofs_N)
148         zz1_elem_N.append(zz1_N)
149
150     # ----------------------------------------------
151     # Results
152     # ----------------------------------------------
153     # Display the convergence of deformation energy
154     ax_Wdef = Display.Init_Axes()
155     ax_error = Display.Init_Axes()
156     ax_times = Display.Init_Axes()
157     ax_zz1 = Display.Init_Axes()
158
159     print(f"\nWSA = {np.round(WdefRef, 4)} mJ")
160
161     for e, elemType in enumerate(elemTypes):
162         # Convergence of deformation energy
163         ax_Wdef.plot(dofs_elem_N[e], wDef_elem_N[e])
164
165         # Error in deformation energy
166         Wdef = np.array(wDef_elem_N[e])
167         error = (WdefRef - Wdef) / WdefRef * 100
168         ax_error.loglog(dofs_elem_N[e], error)
169
170         # Computation time
171         ax_times.loglog(dofs_elem_N[e], times_elem_N[e])
172         # ax_Times.plot(listDofs_e_nb[e], listTimes_e_nb[e])
173         # ax_Times.set_xscale('log')
174
175         # ZZ1
176         if elemType == elemTypes[0]:
177             last = ax_zz1.loglog(dofs_elem_N[e], error, label=f"{elemType}")
178             ax_zz1.loglog(
179                 dofs_elem_N[e],
180                 zz1_elem_N[e],
181                 ls="--",
182                 color=last[0]._color,
183                 label=f"{elemType} (ZZ1)",
184             )
185
186     WdefRefArray = np.ones_like(dofs_elem_N[0]) * WdefRef
187     WdefRefArray5 = WdefRefArray * 0.95
188     # WdefRefArray5 = WdefRefArray * 1
189
190     # Deformation energy
191     ax_Wdef.grid()
192     ax_Wdef.set_xlim([-10, np.max(dofs_elem_N[0])])
193     ax_Wdef.set_xlabel("Degrees of Freedom (DOF)")
194     ax_Wdef.set_ylabel("Strain energy W [mJ]")
195     ax_Wdef.legend(elemTypes)
196     # ax_Wdef.fill_between(dofs_N, WdefRefArray, WdefRefArray5, alpha=0.5, color='red')
197     ax_Wdef.fill_between(dofs_N, WdefRefArray, WdefRefArray5, alpha=0.5, color="red")
198     plt.figure(ax_Wdef.figure)
199     Display.Save_fig(folder, "Energy")
200
201     # Error in deformation energy
202     ax_error.grid()
203     ax_error.set_xlabel("Degrees of Freedom (DOF)")
204     ax_error.set_ylabel("Error W [%]")
205     ax_error.legend(elemTypes)
206     plt.figure(ax_error.figure)
207     Display.Save_fig(folder, "Error")
208
209     # Error in deformation energy
210     ax_zz1.grid()
211     ax_zz1.set_xlabel("Degrees of Freedom (DOF)")
212     ax_zz1.set_ylabel("Error [%]")
213     ax_zz1.legend()
214     plt.figure(ax_zz1.figure)
215     Display.Save_fig(folder, "Error ZZ1")
216
217     # Computation time
218     ax_times.grid()
219     ax_times.set_xlabel("Degrees of Freedom (DOF)")
220     ax_times.set_ylabel("Computation Time [s]")
221     ax_times.legend(elemTypes)
222     plt.figure(ax_times.figure)
223     Display.Save_fig(folder, "Time")
224
225     # Plot the von Mises stress result using 20 color levels
226     Display.Plot_Result(simu, "Svm", ncolors=20)
227
228     if makeParaview:
229         # Generate Paraview files for visualization
230         Paraview.Save_simu(simu, folder, details=True)
231
232     # Show the total computation time
233     print()
234     Tic.Resume()
235
236     # Display the computation time history
237     # Tic.Plot_History(folder)
238
239     # Show all plots
240     plt.show()

Total running time of the script: (0 minutes 5.435 seconds)

Gallery generated by Sphinx-Gallery